DXF downloads bent plate and rolled plate as flat. On a bent plate, a CNC mark is placed 1 inch in from the edge on each end of the bend line. DXF download files are written in the " DXF version " set in " DXF Export Configuration " or, if this is unspecified, in the R10 format.
2 . Press the " Options " button on the CNC Setup window.
3 . The DXF Tool Definition window opens. Click here for information about the options that appear on this window.
Tip: If the " CNC Configuration " listed on the Computer Numerically Controlled window is not the one you want, use the " File " browse button ( ) to select a different configuration or create an entirely new one.
If this box is checked ( ), the Layer Table is disabled , and all tool operations are written to the burn layer.
If the box is not checked ( ), the Layer Table sets the DXF layer you want particular operations to be written to and identifies the operation to be performed on that layer.
( sets the layer you want a tool operation to be written to )
|See the user manual for the CNC machine.||The operation to be performed on the layer.||
The diameter of the hole or slot.
In the primary dimension " Units ."
|The name of the DXF layer to which you want the information for this tool to be output.||The drawing pen number for the layer set in the previous field.|
AutoCAD version: Unspecified (sets version to minimum) or Release 10 or Release 11/12 or Release 13 or Release 14 or 2000 - 2002 or 2004 - 2006 or 2007 - 2009 or 2010 or 2013 . This is the export version of the files that are output when you download DSTV files. After version R14, AutoDesk began to name their versions after the years in which they were released.
Also see: On the Drawing Export Configuration window, you'll also find an " AutoCAD version " option. That option applies to the export of DWG, DXF, DXB and DNG files and is independent of this option.
Download dimensions as: Imperial or Metric . The units that are being used in the current Job are irrelevant to the selection you make here. What is important is the units that are used by the CNC machine you are downloading to.
Select ' Imperial ' if you want data to be output in decimal inches.
Select ' Metric ' if you want data to be output in millimeters.
Reverse polygon direction: or . Downloads for CNC plate burners that read DXF output dictate a particular direction (clockwise or counterclockwise) for cuts interior to the material (for example, holes) and the opposite direction for exterior cuts (such as corner cuts). The direction dictates whether or not the material that is cut away is waste.
If this box is checked ( ), the polygon direction (clockwise vs. counterclockwise) is reversed.
If the box is not checked ( ), the polygon direction specified in the download (clockwise vs. counterclockwise) conforms to the traditional standards.
If this box is checked ( ), then items drawn as line segments in Modeling and the Drawing Editor (for example, copes, slots, curved cuts of any type) are output as arcs from the download file . The plate burner will then be able to cut the item in a smooth arc, probably much more rapidly than if the item was rendered as line segments. Most copes and cuts that are generated automatically or by applying a " Top/bottom flange operation " can be cut more rapidly and cleanly when this option is checked.
If the box is not checked ( ), then items such as copes, slots, etc. are drawn in the download file as line segments. The plate burner will cut the item in linear segments. You might want to use this option for user-applied elliptical cuts that do not convert cleanly to arcs.
If this box is checked ( ), slots are written to the burn layer. Holes will still be punched unless the box is checked for " Burn all holes and slots ."
If this is not checked ( ), a slot is written to whichever punch layer on the " Layer Table " has a diameter that matches the slot diameter.
If this box is checked ( ), an outline of the slot will be drawn around the dot (or dots) that represent the slot.
If this is not checked ( ), a slot overlay will not be included. The dot (or dots) alone will represent the slot.
Exclude bend marks: or . SDS2 downloads bent plates flat, with their bends removed. This option lets you add bend marks to designate where the removed bend was. The option applies only if " Include layout marks in download " is on (checked).
If this box is checked ( ), bend marks are not included in the DXF download file .
If the box is not checked ( ), bend marks are included in the download file to indicate the position of the bend. The bend marks are two CNC marks . Each CNC mark is placed 1 inch in from the edge on each end of the bend line.
Warning : When " Include layout marks in download " is off (not checked), the choice made here does not matter -- you will not get bend marks.
If this box is checked ( ), the exterior outline of a plate is output as a single polyline instead of as separate lines and arcs.
If this is not checked ( ), the exterior outline of a plate is output as separate lines and, where applicable, arcs.
If this box is checked ( ), a command to stencil the submaterial piecemark is generated in the download file . The " Stencil placement " positions the piecemark on the near side of the plate. The stenciled piecemark is the same piecemark for which the download file is named. If the box for " Stencil job name " is also checked, the piecemark is placed after the Job name and separated from it by a space.
If the box is not checked ( ), stenciling of the member piecemark is not performed.
Stencil job name
Stencil job name
If this box is checked ( ), a command to stencil the name of your current Job onto the plate is generated in the download file . The " Stencil placement " positions the Job name on the near side of the plate.
If the box is not checked ( ), stenciling of the Job name is not performed.
If this box is checked ( ), you can enter any string of characters that you want stenciled. Its best to keep the character string short. You might, for example, enter a " Custom stencil " that is the Job number or an abbreviation of the Job name. " Stencil placement " positions the custom stencil on the near side of the plate. If you " Stencil piecemarks " and/or " Stencil job name " in addition to entering a " Custom stencil ," the custom stencil is placed last.
If the box is not checked ( ), custom stenciling is not performed.
Why 'maximum'? The " Stencil height " that you enter here is applied only if there is there is enough room for the stencil to be placed in. If there is not enough room, the height of the stencil is reduced to make it fit.
Tip: If the stencil gets reduced in height so that it can fit, then increase its " Character height/width ratio " and thus make the characters narrower so that the stencil can fit without the character height having to be reduced.
Character height/width ratio: The height-to-width ratio of characters that are stenciled when " Stencil piecemarks " and/or " Stencil job name " are checked. As the following examples show, the actual width of the stencil is equal to the " Stencil height " divided by the " Character height/width ratio ." Consequently, a ratio of ' 2 ' entered here results in a stencil character width of .5 if the " Stencil height " is ' 1 '.
( ht / w )
|height / ratio|
( 1 / .5 )
( 1 /2)
( 1 / 1 )
( 1 /1)
|1||1.5||2/3 or .667 ( 1 / 1.5 )||1.5 ( 1 /.667)|
Stencil placement: Sets the X and Y distance that the stenciled piecemarks and/or Job name are placed from the reference point. If both " Stencil piecemarks " and " Stencil job name " are checked, the Job name is placed first, followed by a space and the piecemark as shown in the illustration below.
|rotation is around the left end of the text|
An entry of ' 0 ' (zero) degrees sets the stenciled characters to be horizontal. That is, parallel with the X axis (length) of the material.
A ' positive number ' of degrees rotates the stenciled characters counterclockwise from horizontal around the left end of the text.
A ' negative (-) number ' of degrees rotates the stenciled characters clockwise from horizontal around the left end of the text.
"OK" (or the Enter key) closes the DXF Tool Definition window. The CNC Setup window again becomes active. Press " OK " on that window to save the choices made on this window to the currently selected " CNC Configuration " file in your current Job .
"Reset" undoes all changes made to this window since you first opened it. The window remains open.