DSTV Options

This window controls the DSTV (.nc1) CNC file options, including what geometry, scribing, header data, and torch information are sent to fabrication machines. These options let you tailor downloads for specific machines and software (such as Ficep, PythonX, or Steel Projects) by adjusting file naming, scribing behavior, material orientation, and DSTV header deviations.

General Overview
Tips and Tricks
Related Tools

General

Options

Include copes and cuts: or .

If this box is checked, the DSTV download file will include instructions for the placement of copes and cuts along with instructions on the placement of holes.

If this box is not checked, the DSTV download file will only include instructions for the placement of holes. The download file will not include copes and cuts.

Also download plates for welded sections: or . This applies when you download a welded plate wide flange or a welded plate box member. Case 2 also applies if you download a welded plate wide flange or a welded plate box submaterial.

Case 1 :
Download plates (too) of welded section
Welded Plate is single material

Case 2 :
Download plates (too) of welded section
Welded Plate is single material

Case 3 :
Download plates (too) of welded section

If this box is checked, four download files will be generated when a welded plate wide flange is selected to be downloaded (1 for the welded section, 1 for the web, 1 for the top flange, 1 for the bottom flange). For a welded plate box , five download files will be generated (1 for the welded plate box section, 1 for the NS web plate, 1 for the FS web plate, 1 for the top flange, 1 for the bottom flange). Be aware that, if you are downloading a member, then whether or not Welded section is single material is checked for a beam or a column or vertical brace affects how the downloaded files are named.

If this box is not checked, one download file will be generated for the welded section.

Case 1 : For a beam or a column or vertical brace on which Welded section is single material is not checked, a welded section will not exist, and you therefore cannot select that section as a submaterial. However, if you download the main material by selecting the member, this option will still apply. The standard CNC plate file naming convention when you Also download plates for welded sections is as follows: member piecemark followed by T or B or R or L for the plate's position, then _ (an underscore), then the submaterial piecemark.

Case 2 : For a beam or a column or vertical brace on which Welded section is single material is checked, the individual plates do not have submaterial piecemarks since the welded section is considered to be a single submaterial. On a member such as a rolled section miscellaneous member or a legacy miscellaneous member , which does not have the Welded section is single material option, welded plate sections are always treated as single material. The standard CNC plate file naming convention when you Also download plates for welded sections is as follows: member piecemark followed by T or B or R or L for the plate's position.

Truncate redundant file names: or . This applies when Download plates (too) is checked and you download a welded plate wide flange or a welded plate box member and Welded section is single material is not checked for a beam or a column or vertical brace and the piecemarking setup option Use member mark for member main material in model is checked.

Truncate...

If this box is checked, file names that are comprised of duplicate strings (one for the member piecemark, the second for the submaterial piecemark), are truncated to a single string. In the example above, B_60T_B_60T.nc1 is truncated to B_60T.nc1. This only affects file names that are comprised of redundant strings -- it does not affect file names that are made up of a member piecemark and submaterial piecemark which are different.

If this box is not checked, file names that are made up of a member piecemark and submaterial piecemark will never be truncated, even when both the member piecemark and the submaterial piecemark are the same.

Do not convert line segments to arcs: or .

If this box is checked, then items such as copes are output from the download file as line segments. The plate burner will cut the item in linear segments. You might want to use this option for user-applied elliptical cuts that do not convert cleanly to arcs.

If this box is not checked, then items drawn as line segments in SDS2 (for example, copes and curved cuts of any type) are output as arcs from the download file. The plate burner will then be able to cut the item in a smooth arc, probably much more rapidly than if the item was rendered as line segments. Most copes and cuts that are generated automatically or which are generated by applying a Top/bottom flange operation ,can be cut more rapidly and cleanly when this option is not checked.

Prefer putting slots on the o or u face: or . This applies to downloads of angles with slots. In the DSTV standard, the o and u faces are on the leg of the angle that is vertical on the CNC machine.

The o and u faces of an angle.

If this box is checked, the SDS2 CNC program will, if necessary, flip the angle so that the leg with the slots are on the o or u face. Consequently, machines with tooling that require slots be on the o or u face will be able to fabricate those slots.

If this box is not checked, the DSTV standard will be followed. The primary leg of the angle (its long leg) will be considered to be N/S, regardless of the location of slots. Most CNC machines use this setting.

Split Files: None or Scribing or Sequence or Both.

None keeps all instances of the same material included in the same.nc1 download file. The file will not include scribing instructions.

Scribing applies to members or materials that are downloaded with the option to scribe Placement marks for.It applies when different placement or piecemark scribing is required for different instances of a material or member with the same piecemark. The SDS2 CNC program will generate a separate file for each scribing need. The files might be named, for example, p3-0.nc1 , p3-1.nc1 , p3-2.nc1 , etc.

Sequence causes downloads of submaterials which run across different sequences to be output in separate files. The files might be named, for example, a45-0.nc1 , a45-1.nc1 , etc., and each file will report the quantity of only those instances of the material that are in the particular sequence.

Both splits the CNC download files by both scribing and sequence.

Note: The option to split files by scribing is mainly for submaterials. However, similar scribing conflicts may occur when you download a member main material by Submaterial. The way to get around this problem for member main material is to, instead, download by Details or Detail sheets -- in which case there will be no scribing conflicts.

Machine Setup

DSTV version: v5.0 or v7.0 .

Select v5.0 to output a download file using DSTV-nc1 version 5 standard.

Select v7.0 to output a download file using DSTV-nc1 version 7 standard.

File extension: .nc1 or .nc or .dat.

.nc1 adds an.nc1 extension (e.g., B_1.nc1 ) to subsequently generated DSTV download files.

.nc adds an.nc extension (e.g., B_1.nc ) to subsequently generated DSTV download files.

.dat adds a.dat extension (e.g., B_1.dat ) to subsequently generated DSTV download files.

Naming of DSTV files: DSTV files are named after either a member piecemark (upper case) or a submaterial piecemark (lower case), depending on how the members or materials are selected. The File extension that is selected here is then added to that name.

Include torch angling: or .

Include torch angling

Include torch angling

If this box is checked, torch angles are included in the download file when, for example, weld preparations and chamfer operations and web cuts are downloaded.

If this box is not checked, torch angles are not included in the download file. This effectively prevents beveled edges from being downloaded. Leave this option not checked if your DSTV viewer cannot handle beveled edges.

Minimum torch angle (abs. value): A positive number of degrees from 0 to 90.

Examples of Torch Angles
(These are all positive angles -- interior to exterior.
The minimum set here also applies to negative angles.)

Effect on the download: Torch angles that are less than the Minimum torch angle will not be downloaded. 0 is vertical and permits any torch angle to be downloaded. An entry of 10 causes only those torch angles that are 10 degrees or more from vertical (clockwise or counterclockwise) to be included in the download file.

A possible application: Suppose that your CNC machine can only handle a single cut on the same edge. This is a problem because the sloping beam with a welded moment connection that you want to download to this machine has two bevel cuts on the same end -- one from the web cut, the other from the field weld preparation. Properly setting a Minimum torch angle is a way for you to get only one cut in the download file.

Max positive angle: The maximum positive angle that you want to allow in the DSTV download file. If the angle of a web cut or field weld prep or etc. exceeds the angle you enter here, that cut will not be included in the download file. Be aware that an angle that is positive in SDS2 may be negative in the DSTV file. See the example below.

This example shows what, in the 3D model, is a single Web cut of 45 degrees . In the DSTV download file, this web cut is two cuts, one positive, the other negative.

Max negative angle: Same as Max positive angle ,except that this applies to negative torch angles in the DSTV file.

In the 3D model, this is one Web cut of 45 degrees . DSTV sees it as two cuts, one positive, one negative. If your Max positive angle was 60 and your Max negative angle was 30, only the positive cut would be included in the download file.

Round torch angle to integer: or . This applies when you choose to Include torch angle in the download file.

Round torch angle to integer

Round torch angle to integer

If this box is checked, torch angles, which are initially calculated to precise decimal values, will each be rounded down to the nearest integer in the download file. Rounding is always down (examples: -18.86 to -19 or 18.86 to 18 ). Users who run Steel Projects software may find this option especially useful.

If this box is not checked, torch angles in the download file will be calculated to precise decimal values.

Download flat bar as plate: or . The following example shows the part of a DSTV file that is affected by this option.

... as plate

If this box is checked, the DSTV download file for the downloaded flat bar will show the Description Prefix for plates instead of the description of the flat bar.

If this box is not checked, the DSTV download file will show the Description Prefix for flat bar, and this description will match the Description that is reported on the General Information window and in the member bill of material.

Note: This option does not apply to a flat bar that was created from a rectangular plate by substituting the description from the Preferred Flat Bar Sizes list. For such a material, DSTV always uses the description prefix for plates, regardless of the choice made here.

DSTV header deviations

Include filename in comment: or .

Include filename...

If this box is checked, the DSTV header will include a comment (marked **) in the header of the file. The comment will indicate the name of the file.

If this box is not checked, the DSTV header will not include a comment indicating the filename.

Omit end cuts from header: or . This applies when the member or material has a Web cut.The DSTV download file's header has two lines ( 18 and 19 in the examples below) for designating web cuts. The first of these lines is for a web cut on the left end, the second is for the right end.

Omit end cuts...

Omit end cuts...

If this box is checked, the value 0.000 is entered to both lines in the header.

If this box is not checked, the number of degrees of the Web cut is entered to the appropriate line ( 18 for the left end, 19 for right end) in the header of the DSTV download file.

Omit drawing info from header: or . This option was added for compatibility with Steel Projects software, but may also apply to other situations.

Omit drawing info...

If this box is checked, the sheet that the drawing is placed on is omitted from the header.

If this box is not checked, the sheet that the drawing is placed on is included in the header. In the example above, the sheet which drawing B_21 is on is named ds_4 as noted in line 3 of the header.

Omit saw length info from header: or . This option was added to accommodate older Ficep machines, but may also be applied to downloads for other machines. It applies when Dimension from saw length is not checked ( ), but the piece would be longer if that option were checked.

Omit saw length

The saw length in this example is 5-0 , which is 1524 mm
(5 x 12 x 25.4).

If this box is checked, only one length value -- the final length -- is reported in the download file.

If this box is not checked, then both values -- the final length and the saw length -- are reported in the download file.

Note: When Dimension from saw length is checked, only one length value -- the saw length value -- is reported, regardless of the choice that is made here.

Omit spaces in section size: or . This option was added for compatibility with WinCad software, which may have problems reading the section size in older machines when there is a space in the section size. Other machines and software may also have this problem. Spaces are conventionally used in the names of imperial section sizes such as the L6x3 1/2x1/2 section in the example below.

Omit spaces from section size

If this box is checked, the section size will be printed in the header without spaces.

If this box is not checked, the section size in the header will be printed as it is in Modeling and the Drawing Editor and Shapes Properties. If it has spaces in Shapes Properties , those spaces will be preserved in the header.

Omit order length in section size for plates: or .

Omit order length...

Omit order length...

If this box is checked, the plate description will consist of the material type ( PL in the above example) and the thickness ( 3/8 ).

If this box is not checked, the plate description will consist of the material type ( PL in the above example), the thickness ( 3/8 ), and the Order length ( 6 ).

Swap section height and width for W tees: or .

Swap...

Swap...

If this box is checked, the positions of Depth (height) and Flange width (width) are switched in the header of the DSTV download file.

If this box is not checked, the header shows the width and height of the W tee in their normal positions.

DSTV deviations

Output non-zero diameter for hole marks: or .

Output non-zero diameter

If this box is checked, CNC hole marks are output to the DSTV download file with a diameter of 0.01 instead of 0.00.

If this box is not checked, CNC hole marks are downloaded with a diameter of 0.00.

Output each hole mark in a separate block: or .

Output... in separate block

If this box is checked, each CNC mark is placed in its own Hole marks block in the DSTV download file.

If this box is not checked, a Hole marks block may include more than one CNC mark.

Output simplified curve information: or .

Curve information is used to describe any radiused or curved cut, including cope radii (as shown), cut layouts made with Corner Rounding turned on, and Exact Fits to a radiused material such as a pipe.

If this box is checked, curved or radiused cuts are output to the DSTV download file using less information. The Steel Projects software used for Ficep machines requires curve information to be output this way. This also works for other software programs.

If this box is not checked, curves are output with more information. One or two additional lines may appear in the download file as a result.

Output with legacy curve directions : or . This option configures the download file so that the contour of a rolled section ( wide flange , tube , etc.) correctly depicts the radius of the cut.

	A top flange contour with cut radii that are convex instead of concave.
	The same top flange, as it is supposed to look in your software.

Check this box if the radius of the cut appears to be bubbled out (convex) rather than in (concave). After you Download the file again, the cut radius should look like is supposed to look.

Leave the box not checked if the cut tube section looks like it is supposed to look when the DSTV file is viewed using your software.

Flip web on Y axis for all material: or . This option was added for use with Peddimat software and for Ficep machines. It applies to all material types.

	A wide flange web that is flipped vertically. Note that the top and bottom flanges are not flipped.
	The same wide flange web, as it is supposed to look in your software.

Check this box if plates (or the webs of wide flanges, channels or other material types) appear to be flipped vertically when viewed in your software. After you Download the file again, the plates (or webs) will be flipped so that they appear like they are supposed to.

Leave the box not checked if plates (or the webs of wide flanges, etc.) look like they are supposed to look when the DSTV file is viewed using your software.

WTee stem: Up or Down or Right or Left.

' Up

' Down

' Right

' Left

Up orients the W tee stem up in the DSTV download file. Down orients the W tee stem down. Right orients the W tee stem toward the right. Left orients the W tee stem toward the left.

Flip WTee stem: or . This option lets you configure the download file so that W tee stems are shown correctly in the viewer you use to view that file.

	A W tee whose stem is flipped vertically , so that it appears upside-down. The flange is not flipped -- only the stem is flipped.
	The same W tee , as it is supposed to look in your software.

Check this box if the W tee stem in a DSTV download file looks like it is flipped vertically, so that it appears to be upside-down when the download file is viewed with your DSTV viewer (as in the top example). After you Download the file again, the stem will be flipped so that it will look like it is supposed to look when viewed in your software (as in the bottom example).

Leave the box not checked if the stem of a W tee is oriented it is supposed to be oriented when the DSTV file is viewed using your software.

Output angle contours and holes on outside faces: or . This option was added for PythonX users.

If this box is checked, angle contours and holes are output on faces h and u.

If this box is not checked, angles are downloaded with faces v and u. This is the default setting and is the way that the DSTV has traditionally behaved.

Flip angle toes: or . This option lets you configure the download file to compensate for differences in how angles are represented in different DSTV viewers.

Flip angle toes

If this box is checked, the angle is flipped horizontally. If the toe direction had been away from you, it will now be toward you.

If this box is not checked, the angle is oriented as it was in versions of SDS2 earlier than v7.134.

Flip column webs: or . This lets you configure the download file so that the contour of a wide flange or tube (HSS rectangular) column web is correctly depicted in the DSTV viewer you use to look at that file. This option was added for users of VersaFab on Python X machines, but may also apply to other situations.

	A column web that is flipped vertically. Note that the top and bottom flanges are not flipped.
	The same column web, as it is supposed to look in your software.

Check this box if the webs of wide flange or HSS rectangular columns look like they are flipped vertically when viewed in your software (as in the top example). After you Download the file again, the webs will be flipped so that they appear like they do in the bottom example.

Leave the box not checked if webs of wide flanges look like they are supposed to look when the DSTV file is viewed using your software.

Omit tube far-side output: or . This may apply when you download tube sections to older Ficep machines. It is required for older Ficep machines running Arianna.

If this box is checked, only three contours will be included in the DSDV header. The far-side web contour will be omitted. This will enable the Ficep machine to properly read-in the DSTV file.

If this box is not checked, the header in the DSTV file will include four contours: top , bottom , near-side web , far-side web.

Flip channel web: or . This option lets you configure the download file so that channel web holes and cuts are shown correctly in the DSTV viewer you use to look at that file.

	A channel web that is flipped vertically. Note that the top and bottom flanges are not flipped.
	The same channel web, as it is supposed to look in your software.

Check this box if channel webs in the DSTV download file look like they are flipped vertically, so that they appear to be upside-down when the download file is viewed with a DSTV viewer (as in the top example). After you Download the file again, the webs will be flipped so that they appear like they do in the bottom example.

Leave the box not checked if channel webs look like they are supposed to look when the DSTV file is viewed using your software.

Flip far side scribing: or . This option lets you configure the download file so that far-side scribing is shown correctly in the DSTV viewer you use to view that file.

	Far-side scribing that is flipped vertically.
	The same scribing, as it is supposed to look in the DSTV viewer.

Check this box if far-side scribing in the DSTV download file appears to be flipped vertically when viewed in your software (as in the top example). After you Download the file again, the scribing will be flipped so that it appears like it does in the bottom example.

Leave the box not checked if far-side scribing looks like it is supposed to look when the DSTV file is viewed using your software.

A special case: For plates, this applies to more than just far side scribing. It flips the scribing on the other side when Send out plates is Near side or Far side. In other words, when Send out plates is Near side, it flips the scribing on the far side; when Send out plates is Far side, it flips the scribing on the near side.

Text origin: Lower left or Left center. The DSTV standard does not specify the origin for an SI text block. Consequently, manufacturing practices vary. Which choice gives you the best result depends on the manufacturer of the CNC machine that you use.

Lower left is the default origin for scribed test. If using this default causes scribed text to be placed lower than you want it to be, then switch to using Left center as the Text origin.

Left center should be your choice if Lower left results in scribed text being placed lower than you want it to be.

Layout Scribing

Scribe marks on: Wide flange and/or Channel and/or Angle and/or W tee / S tee and/or Tube / HSS and/or Welded sections and/or Plate and/or Flat bar and/or Cold formed C. No matter which choices are made here, scribing around the scribed-to material's k-distance is omitted.

Select the materials that you want to be scribed on.

The options Hole matching marks and/or Placement piecemarks and/or Scribe among group members and/or Framing side mark and/or Weld symbols and/or Submaterial will apply scribing to only those material types that you have selected here.

For the most part, scribing is done on member main materials or gusset plates. You can Download member main materials by Details or Detail sheets or, in Modeling , you can Download Members by Location or select member main materials when you Download Material by Location.

Hole matching marks: or . This applies to member main material that has submaterial shop welded to it. A shear plate or end plate or clip angle or gusset plate may shop weld to a member.

Hole matching marks

A shear plate welded to the web of a column. The Lines per hole group is set to All. The scribing of Submaterial is turned on so that the shear plate is scribed, but you would still get the matching marks (in the left example) even if the shear plate was not scribed.

If this box is checked, matching marks are scribed onto a main material to identify the hole center lines in a submaterial that is welded to it. The matching marks are drawn per the Scribe type and Dash length and Lines per hole group.

If this box is not checked, the hole matching marks are not scribed.

Scribe type: Standard or Powdering. This applies when the box is checked for Hole matching marks.

Standard or Powdering are identical with respect to the result that you get when you choose to scribe Hole matching marks. Standard is the scribe type used by most CNC machines.

Dash length: The length of the Hole matching marks.

Lines per material: all or 1 or 2 or more than 2. This applies when the box is checked for Hole matching marks.

1

2

3 or all

All scribes a Hole matching mark through each hole in the material.

1 scribes one Hole matching mark.The line is drawn through the hole that is nearest the left end of the member main material when Orient match marks/ticks to is set to Main material.

2 scribes two Hole matching marks.One line is through the center of the hole that is nearest the left end of the member main material. The other line is through hole that is farthest from the left end.

3 or 4 or ... scribes Hole matching marks through potentially as many holes as the number specified. If the number specified is greater than or equal to the number of holes in the material, the results will be the same as if you had checked the box for All.

Add hole center tick for aligning with hole match mark: or . This applies to materials that shop weld to a member main material.

Add hole center tick

A shear plate. The Ticks per material is set to All.

If this box is checked, tick marks are scribed onto the submaterial (shear plate, end plate, clip angle, gusset plate) as guides for shop placement of that submaterial prior to it being shop welded to its shipping member.

If the box is not checked, tick marks are not scribed onto the submaterial.

Scribe type: Standard or Powdering. This applies when the box is checked for Add hole center tick for aligning with hole match mark.

Standard or Powdering are identical with respect to the result that you get when you choose to Add hole center tick....Standard is the scribe type used by most CNC machines.

Tick length: The length of the tick marks that are scribed for Add hole center tick for aligning with hole match mark.

Ticks per material: all or 1 or 2 or more than 2.

1
2
3 or all

2 or all

Shear plates are shown above.

An end plate is shown at left. For an end plate, each number of Ticks per material results in a pair of ticks being scribed. An end plate shop welds to the web of the supported beam, and the ticks are placed accordingly.

All (checked) scribes a tick for each hole in the material. For an end plate, a pair of ticks are scribed.

1 scribes one tick for the hole that is nearest to the left end of the member main material when Orient hole match marks/ticks to is set to Main materia l.

2 scribes two ticks, one for each of the outside holes.

3 or 4 or ... scribe s the number of ticks that are specified. If the number specified is greater than or equal to the number of holes in the material, the results will be the same as if you had checked the box for All.

Orient hole match marks/ticks to: Submaterial or Main material. This applies when the box is checked for either or both Hole matching marks.and/or Add hole center tick for aligning with hole match mark.The results are the same for either choice if an even number of matching marks or ticks have been designated. You may get different results, depending on the choice made here, when an odd number of marks or ticks have been designated.

Submaterial orients a single match mark and/or tick so that it is closest to a material reference point. Since that reference point is the same for all submaterials with the same piecemark, this can prevent the DSTV submaterial download file from being split into separate files due to scribing.

Main material orients a single match mark and/or tick so that it is closest to the left end of the member main material. This choice may be desirable if you are not using tick marks.

Placement piecemarks: or .

Placement pcmks

If this box is checked, the submaterial piecemark is scribed next to each submaterial that is scribed so long as the condition Place piecemarks for is met. The submaterial piecemark is scribed to the material's right if the material is on the left, to the left if the material is on the right. If materials are not scribed, the piecemark will still be scribed.

If this box is not checked, placement piecemarks will not be scribed.

Placement piecemarks for: Welded or all.

' Welded restricts placement piecemarks to being scribed only for materials that weld to a member in the shop.

' All permits placement piecemarks to be scribed for all submaterials, regardless of whether they shop weld or shop bolt to a member in the shop.

Minimum distance to edge: The distance that the placement piecemark will be placed from the edge of the scribed material.

Framing side mark: or . A framing side mark is used for erection purposes to show on which side of a shear plate to frame the supported beam or vertical brace gusset plate that bolts to that shear plate.

A framing side mark is 1 x 1 inch (25.4 x 25.4 mm). It is scribed to show the framing side of a shear plate.

A framing side mark and a shear plate (Outline) and a Weld symbol.

If this box is checked, a framing side mark is scribed to designate the framing side of a shear plate if the Scribe type is Standard or Powdering. If the Scribe type is Hole marks, the framing side is identified with a CNC mark instead of the symbol. If the Scribe type is Text, the CNC machine stencils a Character instead of scribing the symbol.

If this box is not checked, the framing side mark is not scribed.

Tip: You get a similar framing side symbol on member details if the box is checked for Home > Project Settings > Fabricator > Detailing Symbol Settings > Show paint stripe on framing side of shear plates.That setup option does not have to be checked to get a framing side mark for CNC.

Scribe type: Standard or Powdering or Hole marks or Text.

Standard or Powdering allow the scribing of a Framing side mark that is like the one pictured above. Standard is the scribe type used by most CNC machines.

Hole marks does not allow true scribing, but instead applies a single CNC mark to identify the framing side of the shear plate.

Text results in the framing mark being stenciled using the Character that you specify below.

Character: This option is enabled when the framing side mark Scribe type is Text. Type in a character that is supported in the stencil alphabet that is used by the CNC machine that will be reading the CNC file. The character will be stamped as the Framing side mark on the side of the shear plate that the supported beam frames to. If you type in a character that is not in the CNC machine's stencil alphabet, the machine may substitute a different character or may not give you a character at all. The default entry to the framing side Character is an X.

Weld symbols: or . The weld must exist in Modeling for you to get its symbol.

A weld symbol and a shear plate (Outline) and a Framing side mark.

If this box is checked, weld symbols, including their pointers and tail text, are scribed in a manner similar to the way they are drawn on the actual member detail. The information for the weld symbol originates from the 3D model , not the member detail.

If this box is not checked, weld symbols are not scribed.

Submaterial: or .

If this box is checked, scribing of submaterial is turned on.

If this box is not checked, scribing of submaterials is turned off.

Note: If Scribe standard parts as is set to Submaterial, then standard parts are scribed using the Scribe type and Placement lines for submaterial, regardless of whether this option (Submaterial) is checked or not. Similarly, if Scribe among Grouped members is checked, submaterial settings are used.

Placement marks for: Welded or All. This applies not just to member main materials, but also to plates that connection materials can be welded or bolted to. For example, it applies to vertical brace gussets that shear plates or clip angles may be attached to.

Welded formats the download file to include instructions for scribing those submaterials that are shop welded to a member main material or to a plate. This includes user-added as well as system-generated welded material. Only welded submaterial will be included -- bolted submaterial is excluded.

All formats the download file to include instructions for scribing all of a member's submaterials, including those that are shop bolted and shop welded to the member main material.

Keep placement marks away from edges: or .

If this box is checked, placement marks will be offset from the material edge by the value specified in minimum distance to edge.

If this box is not checked, placement marks are placed at the actual material locations.

Minimum distance to edge: The distance the placement marks are set from the material edge when Keep placement marks away from edges is checked.

Keep placement marks away from flanges: or .

If this box is checked, placement marks will be offset from the material flange by the value specified in minimum distance to edge.

If this box is not checked, placement marks are placed at the actual material locations.

Minimum distance to edge: The distance the placement marks are set from the material edge when Keep placement marks away from flanges is checked.

Scribe among group members: or .

If this box is checked, then the assorted Scribing Options for Abutting materials (Placement marks for ,Placement lines ,etc.) will be applied not just to submaterials, but also to submembers of a grouped member which are closer together than 1/16 inch to the main materials of other submembers of the same grouped member.

If this box is not checked, Scribing Options will only apply to submaterials.

Abutting materials or Flush materials:

If ' Abutting materials is selected, you can select angle or channel or pipe or shear stud/ round bar or standard part or tube/HSS or wide flange or W tee to get settings that apply to scribing layouts tor the selected type of material.

If ' Flush materials is selected , you can select Angle or others or plate to get settings that apply to scribing layouts for the selected type of material.

Note: If Scribe among Grouped members is checked, these settings are used to set the Scribe type ,etc. for scribing submember layouts.

Change Options: Scribe/Do Not scribe submaterial in CNC (turn on/off scribing for selected materials).
General Information: Scribe this material onto others (to track if scribing is on/off).

- abutting angle - abutting angle - abutting angle - abutting angle -

Scribe angles : or . To access this option and related settings for scribing angles , select Angle for Abutting materials.

Scribe angles
Scribe angles

For this example, Scribe type is Standard and Placement lines is Outline.

If the boxes for Scribe angles and Submaterial are both checked, scribing of angles is turned on for materials selected for Scribe marks on.The entries you make to Scribe type and Placement lines and Dash length and Only scribe one corner configure how angle shape layouts are to be scribed.

If the box for Scribe angles is not checked, scribing of angle layouts is turned off.

Scribe type: Standard or Powdering or Hole marks. This applies when Submaterial and Scribe angles are checked.

' Standard
' Powdering
Hole Marks

Standard and Powdering are identical with respect to how they affect angle scribing settings such as the Placement lines ,etc. Standard is the scribe type used by most CNC machines.

Hole marks does not allow true scribing, but instead places a mark at each corner when the Placement lines is set to Outline. If Placement lines is set to Corner, three marks are placed at each corner. Set this to Hole marks, for example, if the CNC machine you are downloading to does not support true scribing.

Placement lines: Outline or Corners. This applies when Submaterial and Scribe angles are checked.

' Outline
' Corners

For both of these examples , the Scribe type is either Standard or Powdering.

Outline generates instructions in the download file for scribing a complete outline of each abutting angle wherever that abutting angle overlaps the downloaded material.

Corners works like Outline, except that only the corners of each abutting angle that overlaps the downloaded material are scribed. For the Corners example shown above, Only scribe one corner is not checked.

Dash length: The length when the Placement lines is Corners. Each segment at the corner will be the Dash length.

Only scribe one corner: or . This applies when the Placement lines is Corners. Submaterial and Scribe angles must also be checked for this to apply.

Only scribe one corner
Only scribe one corner

For both examples , Placement lines is Corners and Scribe type is either Standard or Powdering.

If this box is checked, only one corner of the angle will be scribed.

If this box is not checked, all corners of the angle will be scribed.

- flush angle - flush angle - flush angle - flush angle -

Scribe angles : or . To access this option and related settings for scribing flush angles , select Angle for Flush materials.

Scribe angles
Scribe angles

For this example, Scribe type is Standard and Placement lines is Outline.

If the boxes for Scribe angles and Submaterial are both checked, scribing of angles is turned on for materials selected for Scribe marks on.The entries you make to Scribe type and Placement lines and Dash length and Gap at least and Draw line indicating opposite side leg configure how angle shape layouts are to be scribed.

If the box for Scribe angles is not checked, scribing of angle layouts is turned off.

Scribe type: Standard or Powdering or Hole marks. This applies when Angle is selected for Flush materials and Submaterial and Scribe angles are checked.

' Standard
' Powdering
Hole Marks

Standard and Powdering are identical with respect to how they affect angle scribing settings such as the Placement lines ,etc. Standard is the scribe type used by most CNC machines.

Hole marks does not allow true scribing, but instead places a mark at each corner when the Placement lines is set to Outline. If Placement lines is set to Corner, three marks are placed at each corner. Set this to Hole marks, for example, if the CNC machine you are downloading to does not support true scribing.

Placement lines: Outline or Corners or Dashed. This applies when Angle is selected for Flush materials and Submaterial and Scribe angles are checked.

Outline
' Corners

' Dashed

For all three examples, Placement piecemarks is checked.

Outline generates instructions in the download file for scribing a complete outline of the angle wherever that angle is flush to the downloaded material.

Corners works exactly like Outline, except that only the corners of the flush angle are scribed.

Dashed works like Corners, except that additional dashes are placed between the corners using the Dash length and Gap at least specified below.

Dash length: The length when the Placement lines is Dashed or Corners.

For a Dashed placement line , each dash will be the Dash length ,and the spaces between dashes will be, at least, the Gap at least specified below.

For a Corners placement line , each segment at the corner will be the Dash length.

Gap at least: The minimum distance between dash segments when Placement lines is Dashed.

Draw line indicating opposite side leg: or .

Draw line...
Draw line...

For this example, Scribe type is Standard and Placement lines is Outline.

If this box is checked, a line will be drawn to indicate the thickness of the outstanding leg of the angle.

If this box is not checked, the angle will be represented by a rectangle, without a line indicating the thickness of the outstanding leg.

- flush other - flush other - flush other - flush other - flush other -

Scribe other flush materials: or . To access this option and related settings for scribing other flush materials (W, C, WT, HSS) , select Other for Flush materials.

Scribe other...
Scribe other...

For this example, Scribe type is Standard and Placement lines is Outline. The material could be a wide flange or W tee or channel.

If the boxes for Scribe other flush materials and Submaterial are both checked, scribing of other flush materials can be done on those materials selected for Scribe marks on.The entries you make to Scribe type and Placement lines and Dash length and Gap at least configure how the layouts are to be scribed.

If the box for Scribe other flush materials is not checked, scribing of W, C, WT and HSS flush material layouts is turned off.

Scribe type: Standard or Powdering or Hole Marks. This applies when Submaterial and Scribe other flush materials are checked.

' Standard
' Powdering
Hole Marks

Standard and Powdering are identical with respect to how they affect other settings for flush material scribing (e.g., Placement lines). Standard is the scribe type used by most CNC machines.

Hole marks does not allow true scribing, but instead places a mark at each corner when the Placement lines is set to Outline. If Placement lines is set to Corner, three marks are placed at each corner ( = ). Set this to Hole marks, for example, if the CNC machine you are downloading to does not support true scribing.

Placement lines: Outline or Corners or Dashed. This applies when Other is selected for Flush materials and the boxes for Submaterial and Scribe other flush materials are checked.

Outline
' Corners

' Dashed

Outline generates instructions in the download file for scribing a complete outline of the other material (W, C, WT, HSS) wherever that material is flush to the downloaded material.

Corners works exactly like Outline, except that only the corners of the flush material (W, C, WT, HSS) are scribed.

Dashed works like Corners, except that additional dashes are placed between the corners using the Dash length and Gap at least specified below.

Dash length : The length of the dash when Placement lines is set to Dashed or Corners.

For a Dashed placement line , each dash will be the Dash length ,and the spaces between dashes will be, at least, the Gap specified below.

For a Corners placement line , each segment at the corner will be the Dash length.

Gap at least : The minimum distance (in the primary dimension Units or other units ) when Placement lines is set to Dashed.

- plates - plates - plates - plates -

Scribe plates: or . To access this option and related settings for scribing plates , select Plates for Flush materials.

Scribe other...
Scribe other...

For this example, Scribe type is Standard and Placement lines is Outline.

If the boxes for Scribe plates and Submaterial are both checked, scribing of plates can be done on those materials selected for Scribe marks on.The entries you make to Scribe type and Placement lines and Dash length and Gap at least configure how the plates are to be scribed.

If the box for Scribe plates is not checked, scribing of plates is turned off.

Scribe type: Standard or Powdering or Hole Marks. This applies when Plates is selected for Flush materials and the boxes for Submaterial and Scribe plates are checked.

' Standard
' Powdering
Hole Marks

Standard and Powdering are identical with respect to how they affect plate scribing settings such as the Placement lines ,etc. Standard is the scribe type used by most CNC machines.

Hole marks does not allow true scribing, but instead places a mark at each corner when the Placement lines is set to Outline. If Placement lines is set to Corner, three marks are placed at each corner. Set this to Hole marks, for example, if the CNC machine you are downloading to does not support true scribing.

Placement lines: Outline or Corners or Dashed. This applies when Plates is selected for Flush materials and the boxes for Submaterialand Scribe plates are checked.

Outline
' Corners

' Dashed

Outline generates instructions in the download file for scribing a complete outline of a plate material that is flush to the downloaded material.

Corners works exactly like Outline, except that only the corners of the flush material (W, C, WT, HSS) are scribed.

Dashed works like Corners, except that additional dashes are placed between the corners using the Dash length and Gap at least specified below.

Dash length : The length of the dash when Placement lines is set to Dashed or Corners.

For a Dashed placement line, each dash will be the Dash length ,and the spaces between dashes will be, at least, the Gap specified below.

For a Corners placement line, each segment at the corner will be the Dash length.

Gap at least : The minimum distance between dashes when Placement lines is set to Dashed.

- channel - channel - channel - channel -

Scribe channels : or . To access this option and related settings for scribing channels , select Channel for Abutting materials.

Scribe channels
Scribe channels

For this example , Scribe type is Standard and Placement lines is Outline.

If the boxes for Scribe channels and Submaterial are both checked ( ), scribing of channel shapes is turned on for materials selected for Scribe marks on.The entries you make to Scribe type and Placement lines and Dash length and Scribe corner count and Multiplier for line along web configure how the channel shape layouts are to be scribed.

If the box for Scribe channels is not checked ( ), scribing of channel layouts is turned off.

Scribe type: Standard or Powdering or Hole Marks. This applies when Submaterial and Scribe channels are checked.

' Standard
' Powdering
Hole Marks

Standard and Powdering are identical with respect to how they affect channel scribing options such as the Placement lines, etc. Standard is the scribe type used by most CNC machines.

Hole marks does not allow true scribing, but instead places a mark at each corner when the Placement lines is set to Outline. If Placement lines is set to Corner, three marks are placed at each corner. Set this to Hole marks, for example, if the CNC machine you are downloading to does not support true scribing.

Placement lines: Outline or Corners. This applies when Submaterial and Scribe channels are checked.

' Outline
' Corners

For both of these examples, the Scribe type is either Standard or Powdering.

Outline generates instructions in the download file for scribing a complete outline of each abutting channel wherever that abutting channel overlaps the downloaded material.

Corners works like Outline, except that only the corners of each channel that overlaps the downloaded material are scribed. For theCorners' example shown above, the Multiplier for line along web is 2 and the Scribe corner count is 2.

Dash length: The length when the Placement lines is Corners. Each segment at the corner will be the Dash length so long as the Multiplier for line along web is set to 1.

Scribe corner count: 1 or 2. This applies when the Placement lines is Corners. Submaterial and Scribe channels must also be checked for this to apply.

' 1
' 2

For both examples, the Multiplier for line along web is 2 and the Scribe corner count is 2.

Multiplier for line along web: The factor (a decimal number) by which you want to multiply the Dash length when Placement Lines is Corners and the line segment of a corner is parallel with the web of the channel.

1
2
3

- pipe - pipe - pipe - pipe - pipe -

Scribe pipes : or . To access these settings for scribing HSS round material, select Pipe for Abutting materials.

Scribe pipes
Scribe pipes

If the boxes for Scribe pipes and Submaterial are both checked, scribing of pipes and HSS round shapes is turned on for materials selected for Scribe marks on.The entry you make to Scribe type configures how the pipe shape layouts are to be scribed.

If the box for Scribe pipes is not checked, scribing of pipe and HSS round layouts is turned off.

Scribe type: Standard or Powdering. This applies when Submaterial and Scribe pipe are checked.

' Standard
' Powdering

Standard and Powdering are identical with respect to how they affect scribing options such as the Placement lines ,etc. Standard is the scribe type used by most CNC machines.

- shear stud and round bar - shear stud and round bar -

Scribe round bars and shear studs : or . To access shear stud and round bar scribe settings, select Shear stud/Round bar for Abutting materials.

Scribe round bars and shear studs
Scribe round bars and shear studs

In this example, the Scribe shape is X.

If the boxes for Scribe round bars and shear studs and Submaterial are both checked scribing of round bars and shear studs is turned on. You can make entries to Scribe type and Scribe diameter of and Scribe shape to configure how the round bar and shear stud layouts are to be scribed.

If the box for Scribe round bars and shear studs is not checked, scribing of round bars and shear studs is turned off.

Note: If Scribe standard parts as is set to Shear studs, then standard parts are scribed using the Scribe type for shear studs regardless of whether this option is checked or not.

Scribe type: Standard or Powdering or Hole marks. This applies when Placement marks for is set to All or Welded and when Submaterial and Scribe round bars and shear studs are checked.

Standard or Powdering results in the shear stud being scribed in an L (or X) shape, which represents the stud diameter per the choice made to Scribe diameter of.

Hole marks does not allow true scribing, but instead places a CNC mark at the center of the shear stud (L or X = *). You might set this to Hole marks, for example, if the CNC machine you are downloading to does not support true scribing.

Scribe diameter of: Rod or Head. Scribing of shear studs may be done when Placement marks for is set to All or Welded. This applies when the Scribe type is Standard or Powdering. Round bars do not have heads, which means that round bar scribing will effectively ignore the choice made here.

Rod Head

Rod makes each line segment of the L a length that is equal to the Stud diameter.When the Scribe shape is X , the distance is also the length of either of the two line segments.

Head makes the two line segments of the L or X of a shear stud to each be a length that is equal to the shear stud's Head diameter.

Scribe shape: L or X. This applies when the Scribe type is Standard or Powdering.

L scribes the shear stud or round bar with an L shape

X scribes the shear stud or round bar with an X shape.

- standard parts - standard parts - standard parts -

Scribe standard parts : or . To access these settings for scribing standard parts , select Standard parts for Abutting materials.

If the boxes for Scribe standard parts and Submaterial are both checked, scribing of standard parts is turned on for materials selected for Scribe marks on.The entry made to Use the same options as lets you configure how standard part layouts will be scribed.

If the box for Scribe standard parts is not checked, scribing of standard part layouts is turned off.

Use the same options as: Plates or Shear studs. A standard part can be created in Modeling using Fuse Material. DSTV is able to scribe a standard part onto the surface of a material if the standard part is sufficiently close (within 1/16 inch) of the surface.

Plates causes the the standard part to be scribed as an outline using the Scribe type and Placement lines ,etc. that are used for plates. You might want to do this, for example, if the standard part is flush to the downloaded material.

Shear studs causes the standard part to be scribed in the same way that shear studs are scribed, using the scribing settings for shear stud Scribe type and shear stud Scribe shape ,etc. You might want to do this, for example, if the standard part abuts to the downloaded material like a shear stud.

- tube/HSS - tube/HSS - tube/HSS - tube/HSS -

Scribe HSS and tubes : or . To access these settings for scribing tube/HSS, select Tube/HSS for Abutting materials.

Scribe HSS and tubes
Scribe HSS and tubes

If the boxes for Scribe HSS and tubes and Submaterial are both checked, scribing of tube or HSS rectangular shapes is turned on for materials selected for Scribe marks on.You can make entries to Scribe type and Placement lines and Dash length to configure how HSS and tube shape layouts are to be scribed.

If the box for Scribe HSS and tubes is not checked, scribing of HSS and tube layouts is turned off.

Scribe type: Standard or Powdering or Hole marks. This applies when Submaterial and Scribe HSS and tubes are checked.

' Standard
' Powdering
Hole Mark

Standard and Powdering are identical with respect to how they affect scribing options such as the Placement lines ,etc. Standard is the scribe type used by most CNC machines.

Hole marks does not allow true scribing, but instead places a mark at each corner when the Placement lines is set to Outline. If Placement lines is set to Corner, three marks are placed at each corner. Set this to Hole marks, for example, if the CNC machine you are downloading to does not support true scribing.

Placement lines: Outline or Corners. This applies when Submaterial and Scribe HSS and tubes are checked.

' Outline
' Corners

Outline generates instructions in the download file for scribing a complete outline of each abutting HSS or tube wherever that material overlaps the downloaded material.

Corners works like Outline, except that only the corners of each HSS or tube that overlaps the downloaded material are scribed.

Dash length: The length when the Placement lines for the tube/HSS section is Corners. Each segment at the corner will be the Dash length.

- wide flange - wide flange - wide flange - wide flange -

Scribe wide flange : or . To access these settings for scribing wide flange , select Wide flange for Abutting materials.

Scribe wide flange
Scribe wide flange

If the boxes for Scribe wide flange and Submaterial are both checked, scribing of wide flange shapes is turned on for materials selected for Scribe marks on.You can make entries to Scribe type and Placement lines and Dash length and Include corners and Multiplier for line along flange to configure how wide flange shape layouts are to be scribed.

If the box for Scribe wide flange is not checked, scribing of wide flange layouts is turned off.

Scribe type: Standard or Powdering or Hole marks. This applies when Submaterial and Scribe wide flange are checked.

' Standard
' Powdering
Hole Marks

Standard and Powdering are identical with respect to how they affect scribing options such as the Placement lines ,etc. Standard is the scribe type used by most CNC machines.

Hole marks does not allow true scribing, but instead places a mark at each corner when the Placement lines is set to Outline. If Placement lines is set to Corner, three marks are placed at each corner. Set this to Hole marks, for example, if the CNC machine you are downloading to does not support true scribing.

Placement lines: Outline or Corners. This applies when Submaterial and Scribe wide flange are checked.

' Outline
' Corners

Outline generates instructions in the download file for scribing a complete outline of each abutting wide flange wherever that material overlaps the downloaded material.

Corners works like Outline, except that only the corners of each abutting wide flange that overlaps the downloaded material are scribed. For the Corners example shown above, the Multiplier for line along flange is set to 2.

Dash length: The length when the Placement lines for the wide flange section is Corners. Each segment at the corner will be the Dash length so long as the Multiplier for line along flange is 1.

Include corners: Top flange left and/or Top flange right and/or Bottom flange left and/or Bottom flange right. This applies when Placement lines is set to Corners.

Outlines are shown in this illustration for reference, to help you more easily identify which corner is which. This option only affects the download file when Placement lines is set to Corners.

If the box for a corner is checked, instructions to show that corner will be included in the download file.

If the box for a corner is not checked, that corner will not be shown in the DSTV viewer used to look at that file.

Multiplier for line along flange: The factor (a decimal number) by which you want to multiply the Dash length when Placement lines is Corners and the line segment of a corner is parallel with the flanges of the wide flange.

- W tee - W tee - W tee - W tee - W tee -

Scribe Wtees : or . To access these settings for scribing W tee , select W tee for Abutting materials.

Scribe Wtees
Scribe Wtees

If the boxes for Scribe Wtee and Submaterial are both checked, scribing of W tee layouts is turned on for materials selected for Scribe marks on.You can make entries to Scribe type and Placement lines and Dash length and Scribe corner count and Multiplier for line along flange to configure how W tee shapes are to be scribed.

If the box for Scribe W tee is not checked, scribing of W tee layouts is turned off.

Scribe type: Standard or Powdering or Hole marks. This applies when Submaterial and Scribe W tee are checked.

' Standard
' Powdering
Hole Marks

Standard and Powdering are identical with respect to how they affect scribing options such as the Placement lines ,etc. Standard is the scribe type used by most CNC machines.

Hole marks does not allow true scribing, but instead places a mark at each corner when the Placement lines is set to Outline. If Placement lines is set to Corner, three marks are placed at each corner. Set this to Hole marks, for example, if the CNC machine you are downloading to does not support true scribing.

Placement lines: This applies when Submaterial and Scribe W tee are checked.

' Outline
' Corners

Outline generates instructions in the download file for scribing a complete outline of each abutting W tee wherever that material overlaps the downloaded material.

Corners works like Outline, except that only the corners of each W tee that overlaps the downloaded material are scribed. For the Corners example shown above, the Multiplier for line along flange is set to 2.

Dash length: The length when the Placement lines for the wide flange section is Corners. Each segment at the corner will be the Dash length so long as the Multiplier for line along flange is 1.

Scribe corner count: 1 or 2. This applies when the Placement lines is Corners. Submaterial and Scribe W tee must also be checked for this to apply.

' 1
' 2

' 1 causes only the left corner of the top flange of the W tee to be scribed, along with the bottom of the stem.

' 2 causes both corners of the top flange of the W tee to be scribed.

Multiplier for line along flange: The factor (a decimal number) by which you want to multiply the Dash length when Placement lines is Corners and the line segment of a corner is parallel with the flange of the W tee.

' 1

' 2

' 3

Informational Scribing

Scribe text

Scribe piecemark: or .

Scribe piecemark

Scribe piecemark

If this box is checked, a command to scribe the piecemark is generated in the download file. The scribed piecemark is the same piecemark for which the download file is named. Text block placement positions the piecemark on the left end of the web, near side and/or top flange of the material. If the box for Scribe job name is also checked, the piecemark is placed after the Job name and separated from it by a space.

If this box is not checked, scribing of the member piecemark is not performed.

Scribe job name: or .

Scribe job name

If this box is checked, a command to scribe onto the material the name of your current Job is generated in the download file. Text block placement positions the Job name on the web, near side and/or top flange of the material.

If this box is not checked, scribing of the Job name is not performed.

Custom text: or .

If this box is checked, you can enter any string of characters that you want scribed. It's best to keep the character string short. You might, for example, enter Custom text that is the Job number or an abbreviation of the Job name. Text block placement positions the custom text. If you Scribe piecemark and/or Scribe job name in addition to entering Custom text ,the custom text is placed last.

If this box is not checked, custom text scribing is not performed.

Scribe type: Text or Powdering or Standard. This sets the block that is used for Scribe piecemark Scribe job name and Custom text.

Text lets the font that is used for stenciling be designated by the CNC machine. Usually the characters are stamped onto the surface.

Powdering or Standard scribe types apply the font that auto detailing uses for details. The characters are scribed onto the surface.

Text height: The height of the characters that will be scribed. This applies to characters that are scribed when Scribe piecemark and/or Scribe job name are checked.

Text rotation: A positive or negative number from 999 to -999 degrees. This applies to characters that are scribed when Scribe piecemark and/or Scribe job name are checked.

rotation is around the left end of the text.

An entry of 0 degrees sets the scribed characters to be horizontal. That is, parallel with the X axis (length) of the material.

A positive number of degrees rotates the scribed characters counterclockwise from horizontal around the left end of the text.

A negative (-) number of degrees rotates the scribed characters clockwise from horizontal around the left end of the text.

Text block placement: This sets the X and Y distance for scribing the piecemark and/or Job name on the Web or Top flange or Both web & flange of the material. As shown in the illustration below, if both Scribe piecemark and Scribe job name are checked, the Job name is placed first, followed by a space then the piecemark. Note: This Text block placement setting may be adjusted in the download file to prevent the Job name or piecemark from overlapping a cope or hole.

' Web

' Top flange

X is the distance from the left end of the material to the left end of the scribed characters. This applies to all material types that are downloadable when DSTV is the CNC configuration type.

Y is the distance from the top flange if Web is selected to the top of the scribed characters. If Top flange is selected, this distance is measured from the far side edge of the top flange to the top of the scribed characters. The Y distance for plates and bars is measured from the top edge of the plate regardless of whether Web or Top flange is selected.

Web places the scribed characters on the near side of the web of the material. For an angle , the reference point is the heel (outside corner) of the angle, and the scribing is placed on the long leg.

Top flange places the scribed characters on the near side of the top flange of the material. This applies to wide flange , S shape , welded plate wide flange , W tee , S tee , channel , tube and angle material. It does not apply to plate or bar materials, which always are scribed on the near side face. For an angle, the scribing is placed on the short leg.

Both puts scribing on both the near side of the web and the top flange.

Angle Side: Inside or Outside.

Inside sets the scribed marks on the inside face of the angle leg.

Outside sets the scribed marks on the outside face of the angle leg.

More scribing options

Center of mass: or . This applies when you download member main materials. You can Download member main materials by Details or by Detail sheet or, in Modeling , you can Download Members by Location or select member main material when you Download Material by Location. The same code that is used for the Center of Mass tool in Modeling is used to calculate the center of mass. The calculation includes the mass of all submaterials that weld or bolt to the member main material, as well as shop bolts.

A center of mass symbol is 2.2 x 2.2 inches (56 x 56 mm). It is scribed on the top flange.

If this box is checked, the center of mass symbol is scribed at the center of mass based on which location is selected for the material if the Scribe type is Standard or Powdering. If the Block type is Hole marks, the CNC machine places a CNC mark instead of the symbol. If the Block type is Text, the CNC machine stencils a Character instead of scribing the symbol.

If this box is not checked, the center of mass symbol is not scribed.

Location: Top flange, Bottom flange, NS of Web, and FS of web. The center of mass symbol is not placed at the actual center of mass, but is projected to the selected member's Top flange, Bottom flange, NS of Web, and/or FS of web from that actual location.

Scribe type: Standard or Powdering or Hole marks or Text.

Standard or Powdering permit the scribing of a Center of mass symbol that is like the one pictured above. Standard is the scribe type used by most CNC machines.

Hole marks does not allow true scribing, but instead places a single CNC mark at the point on the top flange that the center of mass is projected to. Set this to Hole marks, for example, if the CNC machine you are downloading to does not support true scribing.

Text results in the center of mass location being stenciled on the top flange using the Character that you specify below.

Character: This option is enabled when the center of mass Scribe type is Text. Type in a character that is supported in the stencil alphabet that is used by the CNC machine that will be reading the CNC file. The character will be stamped at the Center of mass location on the downloaded piece's top flange. If you type in a character that is not in the CNC machine's stenc

il alphabet, the machine may substitute a different character or may not give you a character at all. The default entry to the center of mass Character is an +.

Scribe copes: or . This option was added for Ficep machines, but may also apply to downloads for other machines.

Scribe copes

If this box is checked, copes will be scribed on the outline of the steel as guides for manually cutting the steel.

If this box is not checked, copes are not scribed, but are included as part of the contour.

Scribe type: Standard or Powdering.

Standard or Powdering permit copes to be scribed.

SDS2 logo: or . This applies when the Scribe type for Submaterial is Standard or Powdering.

CELLPADDING = 0

The SDS2 logo is 3 x 6 inches (76 x 152 mm). It is scribed on the beam web.

If this box is checked, the logo is placed four feet in from the left end so that it is centered at the half-depth of the beam web. It's placement will adjust to avoid holes and copes, but not other scribing.

If this box is not checked, the SDS2 logo is not scribed.

Bend marks: or . Bent plates are downloaded flat, with their bends removed. This option lets you add bend marks to designate where the removed bend was. The option applies only if Include layout marks in download is checked.

If this box is checked, bend marks are included in the download file to indicate the position of the bend. The bend marks are two CNC marks. Each CNC mark is placed 1 inch in from the edge on each end of the bend line.

If this box is not checked, a custom line is not included in the DSTV download file.

Note: When Include layout marks in download is not checked, the choice made here does not matter -- you will not get bend marks.

Scribe custom line: or . This applies to scribing on materials that are selected for Scribe marks on.

If this box is checked, a custom line can be scribed by specifying a Scribe type and Line style and On face and Start line at and End line at.

If this box is not checked, bend marks are not included in the DSTV download file.

Scribe type: Standard or Powdering or Hole marks. This applies when Scribe custom line is checked.

Standard and Powdering are identical with respect to how they affect scribing options such as the Line style, etc. Standard is the scribe type used by most CNC machines.

Hole marks does not allow true scribing, but instead places CNC marks based on the choice made to Line style.

Line style: None or Solid or Dashed or Ends Only. This applies when Scribe custom line is checked. A custom line does not navigate around other scribing or holes -- it does respect the Scribing minimum distance to edge.

None stops a custom line from being generated.

Solid generates a solid line between the Start line at point and the End line at point.

Dashed generates a dashed line between the Start line at point and the End line at point -- each dash is the Dash length and the spaces between dashes will be, at least, the Gap... specified below.

Ends Only generates a one-inch line segment at the Start line at point and another one the End line at point.

Dash length : The length when Scribe custom line is checked and the Line style is set to Dashed or Ends only.

Gap at least : The minimum distance when Scribe custom line is checked and the Line style is set to Dashed.

On face: Top flange or Web/plate NS or Bottom or Web/plate FS. This applies when Scribe custom line is checked.

Choose the face that you want to scribe the custom line on. For a plate, the only choices that will work are Web/plate NS or Web/plate FS. For a wide flange, all of the choices are valid.

Start line at: The X distance from the bottom of the plate and Y distance from the left edge of the plate that together define the starting point of the line whose Line style is set above. Distance entries can be made in the primary dimension Units or other units. For non-rectangular material faces such as a flat plate layout or round plate or a wide flange with a cope at the lower, left corner, you may want to start at a point that is off the material -- if you do so, the true starting point of the actual scribed line will be just inside the Scribing minimum distance to edge. This applies when Scribe custom line is checked.

A horizontal line	A vertical line

End line at: The X distance from the bottom of the plate and Y distance from the left edge of the plate that together define the end point of the line whose Line style is set above. Distance entries can be made in the primary dimension Units or other units. This applies when Scribe custom line is checked.

A diagonal line

OK (or the Enter key) closes the DSTV Options window. The CNC Setup window again becomes active. Press OK on that window to save the choices made on this window to the currently selected CNC configuration file in your current Job.

Cancel (or the Esc key) closes this window without saving any changes made to it. The CNC Setup window again becomes active.

DSTV can download holes, marks, cuts, weld preparations and chamfer operations to CNC machines that are able to operate on Material types that are set to be downloadable (on the CNC Setup window). Bent plate and rolled plate are downloaded flat.
On a bent plate, a CNC mark is placed 1 inch in from the edge on each end of the bend line.